This case concerns a 2-layer thermoelectric separation copper substrate order measuring 121.44 mm by 348.33 mm, ordered as 15 pieces in five customer-supplied 3×1 panels. The board uses purple copper base material, 1.0 mm overall thickness, 1 oz copper on both outer layers, cold-white solder mask, black silkscreen, and OSP surface finish. During CAM review our team raised four points that required customer confirmation before file release. The points addressed production convenience on the process edge, identification marking, the achievable dielectric thickness between the core and copper base, and the solder-mask treatment of closely spaced pads. The customer subsequently confirmed the file, allowing the proposals to stand as the basis for manufacture.
Copper Base PCB CAM Review: Process-Edge Positioning Holes and Panel Identification
The order ( #CU-20260425-065 ) parameters listed process edge as 0 mm and shipping type as customer self-panel. Even so, the Gerber set contained a narrow process margin that could be used for manufacturing aids without altering the customer outline. Our engineer proposed adding three 2.0 mm positioning holes on that margin. The holes serve as registration points for drilling, routing, and electrical test fixtures. On a long, narrow copper-based panel the added holes reduce the risk of cumulative positioning error that can appear when only the customer outline is used for alignment. Because the holes sit entirely outside the finished board outline, they do not affect the delivered product geometry.

Figure 1: Adding three 2.0 mm positioning holes
In the same communication we asked for confirmation to place a silkscreen number at the location indicated on the process edge. The marking provides a clear panel identification for the production floor and for any subsequent AOI or electrical-test records. With the solder-mask color specified as cold white and the silkscreen as black, the contrast is sufficient for both human and machine reading. The addition is a standard CAM practice when the customer has not already defined a panel identifier and when the process margin allows it. Both items were presented as requests for confirmation rather than unilateral changes; the later file confirmation indicated acceptance.

Figure 2: place a silkscreen number at the location indicated on the process edge
Thermoelectric PCB Dielectric Thickness: 25 µm vs. 150 µm
The central technical clarification concerned the dielectric layer that bonds the circuit core to the copper base. The incoming data requested a 150 µm dielectric. After reviewing the stack-up against our process capability for thermoelectric-separation copper substrates, our engineer noted that 150 µm could not be met. We therefore proposed to build the dielectric at our conventional 25 µm thickness.
On copper-based boards the dielectric is the primary thermal barrier. The order lists a thermal conductivity of 1.0 W and does not require a high-voltage withstand test. Under these conditions a thinner dielectric is the normal construction because it shortens the heat path from the circuit layer to the copper base while still providing the electrical isolation needed for low-voltage applications. A 150 µm layer would increase thermal resistance and is outside the standard lamination window used for this material system; attempting to force that thickness would require non-standard prepreg or adhesive films that are not part of our qualified process for copper-base thermoelectric boards. By stating the limitation explicitly and offering the 25 µm alternative, the EQ allowed the customer to decide whether the thermal performance of the thinner dielectric was acceptable or whether a different construction was required. The subsequent file confirmation resolved the point in favor of the 25 µm dielectric.

Figure 3: The Dielectric between copper and copper base can not fab with 150um
The overall board thickness remains 1.0 mm as ordered. The copper base itself accounts for the majority of that thickness; the dielectric and the thin circuit foil make up only a small fraction. Changing the dielectric from the requested 150 µm to 25 µm therefore has negligible effect on the finished mechanical thickness while producing a measurable improvement in thermal transfer. No other stack-up parameters—copper weight, layer count, or surface finish—were altered by this decision.
Copper Base PCB Solder Mask: Opening Treatment for Narrow Pad Spacing
The second major CAM finding involved solder-mask clearance between adjacent pads. After applying the normal compensation for mask registration and undercut, the remaining space between certain pads measured 0.16 mm. Our minimum reliable solder-mask bridge width is 0.21 mm. A bridge narrower than that limit is prone to incomplete development, residual mask, or outright breakage during processing, any of which can leave conductive residue or create an unreliable dam. Rather than attempt a sub-minimum bridge, our engineer proposed to treat the affected pads as a continuous open window.

Figure 4: The space between the pad is too small
An open-window treatment removes the mask entirely between the pads so that no dam exists. The approach eliminates the risk of a defective bridge while accepting the possibility that solder paste may flow between the pads during assembly. Because the order specifies OSP finish and 100 % AOI, the open areas remain inspectable after fabrication. The proposal was limited to the locations where the measured spacing fell below 0.21 mm; all other mask features retained their designed openings. The customer was asked to confirm the treatment, and the later file confirmation indicated acceptance of the open-window solution.
The line width and spacing listed in the order parameters is 6, consistent with a relatively coarse outer-layer design. The tight pad spacing that triggered the mask issue therefore appears local rather than global. By documenting the measured 0.16 mm clearance and the 0.21 mm process limit, the EQ made the manufacturing constraint transparent and allowed the customer to evaluate whether the open window was compatible with the intended assembly process.
Copper-Based Thermoelectric PCB Manufacturing Requirements
The remaining order parameters supplied useful background but did not drive additional EQ items. The board is a simple two-layer construction with no blind or buried vias, no impedance control, and no HDI features. Hole size is listed as 0.2 mm, hole copper as 18 µm, and plating as immersion copper followed by the exposure process. Forming is mechanical with V-score separation on the customer panel. Test coverage is 100 % AOI plus an electrical-performance test report and quality certificate; no high-voltage test is required. These details confirmed that the board stays within standard copper-base thermoelectric process windows once the dielectric thickness and solder-mask treatment are settled.
The production confirmation flag was already set to "yes" and a factory code was to be added, both of which are routine once the customer accepts the CAM proposals. The engineer grade recorded for the order is intermediate, matching the straightforward nature of the construction once the two technical points were clarified.
CAM Engineering Changes and Customer File Confirmation
All four points—positioning holes, silkscreen number, 25 µm dielectric, and open-window solder mask—were presented together in a single EQ communication. The customer response was limited to file confirmation. That confirmation closed the open items and authorized release of the manufacturing data with the proposed adjustments in place. No further design changes, stack-up revisions, or mask modifications were recorded.
In copper-based thermoelectric work the dielectric thickness and the solder-mask dam capability are two of the parameters that most frequently require explicit CAM clarification. The dielectric directly governs thermal performance, while the mask treatment affects both yield and assembly behavior. By stating the process limits in measurable terms (150 µm not achievable, 25 µm conventional; 0.16 mm clearance versus 0.21 mm minimum bridge) and by offering concrete alternatives, the EQ allowed the customer to make an informed decision without delaying the order. The subsequent file confirmation demonstrates that the proposed construction and mask treatment were accepted as the basis for production.