During CAM preparation of a 6-layer HDI order classified as 2-order, our team identified multiple drill, separation, clearance, and process items that required customer confirmation. The board measures 58 mm by 116 mm, uses Kingboard KB-6165F FR-4 with TG150, is specified at 1.0 mm finished thickness with 1 oz copper, carries blue solder mask and white silkscreen, and requires resin plugging of vias. Blind and buried vias are indicated, the minimum hole size is listed as 0.15 mm, separation is by routing, and the delivery format is customer self-panelization in a 1×2 array with no process edge. Mechanical forming is specified and no impedance control is required. These parameters establish a compact 2-order HDI construction in which laser-drilled blind vias, routing paths, mask openings, and plugging must be explicitly aligned with the supplied data.
The main engineering communications proposed reducing certain blind-via drills on layers 1-2, 1-3, 4-6 and 5-6 to 0.1 mm, asked whether an arrowed location required V-cut separation, noted that a 1 mm routing slot lay too close to internal traces to be fabricated, flagged a hole that lacked a bottom-layer pad and intersected a top-layer trace, confirmed that large fiducial and hole openings would be produced with exposed copper, proposed adding the production number at an arrowed location while allowing copper pour on the process edge, and specified resin plugging of all 0.2 mm and 0.3 mm holes on the through-hole layer. A parallel note restated the diameter reduction of 0.178 mm and 0.254 mm features to 0.1 mm for production convenience.
HDI Blind Via Diameter Adjustment: 0.1 mm Laser Drilling
The data contained drills on layers 1-2, 1-3, 4-6 and 5-6 that measured 0.178 mm and 0.254 mm. We proposed changing these to 0.1 mm for production convenience and requested confirmation. In a 2-order HDI ( #HDI-20251022-0008 ) the blind vias are laser-drilled after each sequential lamination; diameters above approximately 0.15 mm often fall outside the optimal laser window and may require mechanical drilling or risk incomplete ablation. Reducing them to 0.1 mm places the features inside the standard laser process capability while preserving the intended layer-to-layer connections.


Figure 1, 2: These 0.178mm and 0.254mm drill holes on 12 13 46 and 56 layers will be changed to 0.1mm
The order lists a 0.15 mm hole size and indicates resin plugging. The smaller diameter remains compatible with subsequent plating to 18 µm hole-wall copper and with resin fill. Because the board is only 1.0 mm thick, the aspect ratio of a 0.1 mm blind via is manageable. Confirmation of the change locks the laser programs for the affected layer pairs before the sub-composites are drilled. The same reduction was noted twice in the records, underscoring that the adjustment applies consistently across the listed spans.
HDI Panel Separation: Clarifying V-Cut and Routing Requirements
An arrow indicated a location whose purpose was unclear. We asked whether V-cut separation was required at that position. The order form lists separation as routing only and shows a customer self-panelized 1×2 array with no process edge. In such a format the break-away method must be explicit; an unintended V-cut could intersect functional copper or the resin-plugged vias, while the absence of a needed score could leave the two circuits joined.
Because the panelization is customer-supplied, the factory does not generate the array but must still program the mechanical tools to match the intended separation. The query therefore seeks confirmation so that the routing or scoring path can be finalized. On a 1.0 mm board any V-cut depth must be controlled to leave a residual web that separates cleanly without damaging the 2-order structure. Customer instruction on this point determines whether the location remains a routed slot or becomes a scored break.

Figure 3: This position shown by the arrow need to be V-cut
PCB Routing Clearance: Resolving a 1 mm Slot Conflict
A 1 mm routing slot in the original data lay too close to internal traces to be fabricated. We noted the conflict and requested confirmation. Routing clearance must account for tool diameter, registration tolerance, and the minimum copper-to-edge distance on inner layers. When the slot approaches traces more closely than the process allows, the router can nick the copper, creating opens or reducing current-carrying capacity on the 1 oz inner layers.
The order specifies mechanical forming and routing separation. The proximity issue therefore requires either relocation of the slot, reduction of its width, or acceptance of a modified path that restores adequate clearance. Because the board also contains laser-drilled blind vias and resin-plugged holes, the routing path must additionally avoid those features. Confirmation establishes whether the customer will adjust the slot or accept a factory-proposed reroute before the mechanical programs are released.

Figure 4: The 1mm slot in the original file are too close to the board circuit
HDI Via Verification: Missing Pad and Trace Intersection
An arrowed hole showed no pad on the bottom layer and drilled into a trace on the top layer. We requested confirmation of the intended attribute. In HDI PCB designs a via may be blind, buried, or a non-functional transition; the absence of a pad on one side and the intersection with a trace on the other side leave the connectivity and the plating sequence ambiguous. Misclassification can produce an open, a short, or a plating defect that appears only after sequential lamination.
The order indicates blind and buried vias with resin plugging. The flagged feature must be assigned to the correct drill span and plating recipe so that it either connects the intended layers or is treated as a non-plated hole. Because the top-layer intersection occurs on a trace rather than a pad, the annular ring and the subsequent solder-mask opening are also affected. Confirmation clarifies the attribute before the drill files and the resin-plug map are finalized.

Figure 5: These holes as shownby the arrow in the picture are without pads on bottom copper layer
Solder Mask Opening Review: Exposed Copper Around Fiducials and Holes
Fiducials and certain hole openings were drawn larger than the underlying copper. We stated that production would follow the file and expose the copper, and requested confirmation. Blue solder mask normally covers copper except at intentional openings; when the opening exceeds the pad or fiducial, the surrounding copper remains exposed after development. The exposure may be required for optical recognition or for soldering, yet it also leaves the copper subject to the immersion-gold finish and to potential solder bridging if the clearance is unintended.
Because the order specifies resin plugging and via cover is not universally required, the large openings are local exceptions. Confirmation records that the customer accepts the exposed copper as drawn so that no mask compensation is applied. The same openings must remain clear of the routing paths and of any production-number marking added elsewhere on the panel.

Figure 6: The fiducial and the hole openings are larger, we will fabricate as the file to be copper exposed
PCB Production Marking and Process-Edge Copper Pour
The order requires addition of a production number. We proposed placing it at an arrowed location and noted that copper pour is allowed on the process edge, requesting confirmation. Although the order form lists no process edge, a temporary copper border can improve plating-current distribution on a customer self-panelized 1×2 array that otherwise lacks edge support. The production number itself provides traceability for the 10-piece, 5-set delivery.

Figure 7: We will add our factory number at the position shown by the arrow
Placement at the arrowed site keeps the marking outside the functional circuitry and clear of the resin-plugged vias and routing slots. The copper pour, if accepted, is removed with the process edge or routing and does not remain on the finished 58 mm by 116 mm boards. Confirmation of both the location and the pour allowance finalizes the panel marking and the temporary copper before imaging.
HDI Resin Plugging Requirements for 0.2 mm and 0.3 mm Through Holes
The order specifies resin plugging. We proposed that all 0.2 mm and 0.3 mm holes on the through-hole layer receive resin plugs and requested confirmation. Resin plugging fills the via barrels to improve reliability, prevent solder wicking, and provide a flat surface when vias intersect pads. On a 2-order HDI the through holes that remain after the sequential build are the natural candidates for plugging if they fall within the stated diameter range.

Figure 8: All these 0.2mm and 0.3mm holes in the though-hole layer will be fabricated as Resin plug hole
The 0.2 mm and 0.3 mm sizes are larger than the 0.1 mm laser blind vias already discussed and are typically mechanical drills. Plugging them after plating ensures the 18 µm hole-wall copper is encapsulated. Because the order already lists resin plugging and the customer self-panel has no process edge, the plug process must be uniform across the 1×2 array. Confirmation of the diameter range locks the plug map so that only the intended through holes are filled while the laser-drilled blind vias follow their own fill or cover requirements.
6-Layer HDI CAM Review: Via, Routing, and Manufacturing Optimization
The items in the main engineering query address the practical constraints of releasing this 6-layer 2-order HDI board. Reducing the 0.178 mm and 0.254 mm drills to 0.1 mm aligns the blind vias with laser capability. The V-cut query and the 1 mm slot clearance issue define the mechanical separation path on the customer 1×2 panel. The via-attribute flag, the exposed-copper openings, the production-number placement, and the resin-plugging specification complete the drill, mask, marking, and fill requirements.
Each proposal or query requires explicit customer confirmation because the original data either contained via diameters outside the preferred laser window, left the separation method ambiguous, showed a routing conflict, or required clarification of via attributes, mask openings, marking location, and plug scope. Once the 0.1 mm diameters, the separation method, the slot clearance, the via attribute, the exposed-copper treatment, the production-number placement, and the resin-plug diameters are confirmed, the laser programs, routing paths, mask artwork, and plug map can be frozen. The board can then proceed through sequential lamination, laser drilling of the reduced-diameter blind vias, resin plugging of the designated through holes, outer-layer processing, and mechanical forming. The case illustrates how CAM review of a compact 2-order HDI commonly generates a coordinated set of via-diameter, separation, clearance, and process-attribute confirmations that together place the design inside laser, routing, and plugging capability.