During CAM preparation of a 4-layer HDI order classified as 1-order, our team identified several data and specification items that required customer confirmation. The board measures 41.4 mm by 25.4 mm, uses Shengyi S1000H FR-4 with TG150, is listed at 1.6 mm finished thickness with 1 oz copper on outer and inner layers, carries green solder mask and white silkscreen, and includes one-sided half-holes. Blind and buried vias are indicated, the hole size is given as 0.2 mm, via cover with solder mask is specified, and the surface finish is immersion gold at 2U". Delivery uses factory panelization with 10 mm process edges on all sides and routing separation. These parameters describe a compact 1-order HDI construction in which laser-drilled blind vias, mask openings, stackup consistency, and panel format must be aligned before tooling release.
The engineering communications proposed changing the 0.2 mm holes on layers 1-2 and 3-4 to 0.1 mm, confirmed that solder-mask openings exposing copper would be produced according to the file, noted a discrepancy between a customer lamination of 1 mm with half-ounce inner copper and the order-form thickness of 1.6 mm with 1 oz inner copper, and submitted the panel drawing for confirmation.
Blind Via Diameter Adjustment from 0.2 mm to 0.1 mm
The data showed 0.2 mm holes associated with layers 1-2 and 3-4. We proposed fabricating these features at 0.1 mm and requested confirmation. In a 1-order HDI the blind vias that connect the outer layers to the first inner layers are normally laser-drilled; a 0.2 mm diameter sits at the upper end of typical laser capability and may require mechanical drilling or risk incomplete ablation and poor plating. Reducing the diameter to 0.1 mm places the vias inside the standard laser process window while preserving the intended layer-to-layer connectivity.
The order lists a 0.2 mm hole size and indicates blind/buried vias, yet the engineering note specifically targets the 1-2 and 3-4 spans. The change therefore applies to the blind-via drills rather than to any through-hole features. Because the board ( #HDI-20251126-0021 ) is only 41.4 mm by 25.4 mm and uses 1 oz copper, the smaller vias still provide adequate capture-pad registration after laser drilling and subsequent plating to the stated 18 µm hole-wall copper. Confirmation of the 0.1 mm diameter locks the laser program and the corresponding capture-pad artwork before the sequential lamination begins.

Figure 1: educing the diameter to 0.1 mm
Solder-Mask Opening Design for Exposed Copper Areas
A figure showed solder-mask openings that expose underlying copper. We stated that production would follow the file and requested confirmation. Green solder mask is normally applied to protect copper; when an opening is drawn larger than the pad or intentionally clears adjacent copper, that copper remains exposed after imaging and development. The exposure may be required for soldering, grounding, or heat dissipation, yet it also leaves the copper vulnerable to oxidation or solder bridging if the opening is unintended.

Figure 2: solder-mask openings that expose underlying copper
Because the order specifies via cover with solder mask and green mask on both sides, the exposed-copper openings are local exceptions rather than a global change. On a board that also contains one-sided half-holes and immersion gold, the exposed areas will receive the gold finish along with the pads. Confirmation simply records that the customer accepts the openings as drawn so that no mask compensation or copper pull-back is introduced. The same confirmation ensures the openings remain clear of the 10 mm process edges and the routing paths.
Resolving Conflicting HDI Stackup and Copper Specifications
The customer lamination drawing indicated a finished thickness of 1 mm with half-ounce (HOZ) inner copper, while the order form lists 1.6 mm finished thickness and 1 oz inner copper. We flagged the difference and requested confirmation of which values govern. On a 4-layer 1-order HDI PCB the dielectric thicknesses and copper weights determine both the overall board thickness and the laser-drill aspect ratio for the blind vias. A 1 mm stack with HOZ copper produces a different dielectric spacing and a different etch behavior from a 1.6 mm stack with 1 oz copper.

Figure 3: The stack up board thickness 1mm,but when the customer place order choose 1.6mm inner 1oz
The order form also states that no stackup is required and shows Shengyi S1000H material. The discrepancy may arise from an earlier design revision or from a stackup prepared for a different thickness target. Until the governing thickness and inner-copper weight are confirmed, neither the lamination cycle nor the impedance-independent dielectric construction can be finalized. The 0.1 mm blind-via proposal described above remains compatible with either thickness, yet the capture-pad sizes and plating uniformity will differ. Confirmation resolves which construction is released to fabrication.
Factory Panelization Design and Drawing Confirmation
A panel drawing was submitted for confirmation. The order indicates factory panelization with 10 mm process edges on all four sides, a 1×1 base array, and routing separation. The drawing therefore defines the working panel outline, tooling-hole placement, and routing paths that will be used to produce the 41.4 mm by 25.4 mm circuits. Because the board includes one-sided half-holes and laser-drilled blind vias, the panel must provide adequate edge support for mechanical forming and must keep the half-hole edge clear of the process-edge copper.
Confirmation of the panel locks the array format before the routing and scoring programs are generated. The same panel also supports uniform plating current for the immersion-gold finish and for the 18 µm hole-wall copper. Acceptance ensures that the process edges, any added tooling features, and the final break-away method match the customer's expectations for the 10-piece, 10-set delivery.
Key CAM Confirmations for 4-Layer HDI Manufacturing
The engineering items form a concise set of clarifications for this 4-layer 1-order HDI board. Reducing the 0.2 mm holes on the 1-2 and 3-4 spans to 0.1 mm aligns the blind vias with laser capability. Accepting the solder-mask openings that expose copper records the customer's intent for those local features. Reconciling the 1 mm HOZ customer stackup against the 1.6 mm 1 oz order-form values establishes the dielectric and copper construction that will be laminated. Confirming the panel drawing fixes the format in which all of the above are manufactured.
Each point requires explicit customer response because the original data either contained a via diameter outside the preferred laser window, showed mask openings that expose copper, presented conflicting thickness and copper specifications, or required approval of the working panel. Once the 0.1 mm via size, the exposed-copper openings, the governing stackup, and the panel layout are confirmed, the laser drills, mask artwork, lamination cycle, and routing programs can be released. The board can then proceed through inner-layer imaging, sequential lamination, laser drilling of the reduced-diameter blind vias, outer-layer processing, and mechanical forming with the confirmed panel. The case illustrates how CAM review of a small 1-order HDI commonly surfaces a short cluster of via-diameter, mask, stackup-consistency, and panel-format questions that must be resolved together before fabrication begins.